Hi, I'm a mechanical drawer, I'll use Elmer for test tensions on some piece.
I studied and done Tutorial 2 Linear elasticity equation – Loaded elastic beam
Questions:
- Why the volume isn't considered in the formula? Model\BodyForce\Name = Gravity\Linear Elasticity\Force 2 = $ -9.81 * 550
- How to interpret results?
with Gravity I get Displacement_abs = 1.5e+002 instead of 6.36 cm of Tutorial or 6.4 cm by a manual calculation
removing gravity (27 N over 2000 N of load) I get Displacement_abs = -91 and vonmises = max 1.4e+08 (I'm using SI units, so what is it? N/m^2 ?)
Notes: I can't find Directory: ElasticBeam3D\beam3d.grd (installer: Elmer7.0-rev5817-2012-08-22.exe),
so on my CAD program I recreate and export a .step (in mm). If I get some mistake mm <-> m the result could be similar with only a difference of the decimal position, I suppose.
Thanks for explanations.
Displacement and tensions value in a elastic beam
Re: Displacement and tensions value in a elastic beam
Hi,
I think it is indeed the problem of using mm instead of m. You can either scale your mesh with "ElmerGrid" or draw it again.
By the way, you can download stuff at https://elmerfem.svn.sourceforge.net/sv ... fem/trunk/
For example in your case the geometry is here https://elmerfem.svn.sourceforge.net/sv ... mples/grd/
or https://elmerfem.svn.sourceforge.net/sv ... beam3d.grd
Your question:
- The body force is actually a "force density" and not "force". So it is the density of the material that determines the body force on each point of the body. Volume is thus not needed.
- please specify what you mean by "interpreting". In the tutorial picture you can clearly see the corresponding beam bending.
Cheers,
Eelis
I think it is indeed the problem of using mm instead of m. You can either scale your mesh with "ElmerGrid" or draw it again.
By the way, you can download stuff at https://elmerfem.svn.sourceforge.net/sv ... fem/trunk/
For example in your case the geometry is here https://elmerfem.svn.sourceforge.net/sv ... mples/grd/
or https://elmerfem.svn.sourceforge.net/sv ... beam3d.grd
Your question:
- The body force is actually a "force density" and not "force". So it is the density of the material that determines the body force on each point of the body. Volume is thus not needed.
- please specify what you mean by "interpreting". In the tutorial picture you can clearly see the corresponding beam bending.
Cheers,
Eelis
Re: Displacement and tensions value in a elastic beam
Hi,
to use a mesh with mm as length unit write
Coordinate Scaling = 0.001
into the simulation section of your sif (ElmerGUI: free text field in Model->Setup->Simulation).
HTH,
Matthias
to use a mesh with mm as length unit write
Coordinate Scaling = 0.001
into the simulation section of your sif (ElmerGUI: free text field in Model->Setup->Simulation).
HTH,
Matthias
Re: Displacement and tensions value in a elastic beam
Thanks for reply.
my second question was about units, but as I show below my troubles caused by trying to make ends meet keeping for good some wrong data.
I note theese mistakes in the tutorial:
Now I use beam3d.grd:
so Boundary area are:
Tutorial 2 says:
In fact if I set corrected data into ElmerGUI, I keep these results from Post:
Is it right?
Thanks.
my second question was about units, but as I show below my troubles caused by trying to make ends meet keeping for good some wrong data.
I note theese mistakes in the tutorial:
Now I use beam3d.grd:
Code: Select all
BOUNDING BOX
X-coordinate: [ 0 , 0.1 ]
Y-coordinate: [ 0 , 0.05 ]
Z-coordinate: [ 0 , 1 ]
Code: Select all
Z*X = 0.1 m^2
Z*Y = 0.05 m^2
From my knowledge, the approximated formulas are:The second boundary condition distributes
the load of 2000 N uniformly on the area of 5.0e-3 m2 (wrong). <-- 0.1 m^2 Z*X
...
Linear elasticity
Force 2 = -4.0e5 (wrong) <-- -20000 N/m^2
...
The maximum displacement is 6.36 cm (wrong) <-- 0.024 m or 2.4 cm see below
...
Extra task: Gravity in x direction
...
Linear elasticity
Force 1 = -4.0e5 (wrong) <-- -4.0e4 Z*X
Code: Select all
Displacement_y = Force * length^3 / (8 * Youngs_Modulus * I)
I = bh^3/12 = 0.1*0.05^3 /12 = 1.041667e-6 m^4
Displacement_y = (-2027 N * 1 m^3) / (8 * 10*10^9 N/m^2,* 1.0416e-6 m^4) = -0.0243 m
max stress = 3 * length * Force / (b*h^2) = 3* 1 * 2027 / (0.1 * 0.05^2 ) = 24324000 N/m^2
In fact if I set corrected data into ElmerGUI, I keep these results from Post:
Code: Select all
Displacement_y = -0.0239 ("m") OK
Vonmises = 2.3006e+007 ("N/m^2") OK
Is it right?
Thanks.
Re: Displacement and tensions value in a elastic beam
No.
The beam tutorial is correct. The force works on the smallest area of 0.1 * 0.05 = 0.005 m^2. The confusing label "Force" in the Linear Elastic boundary condition is actually a pressure. So you enter something with for example the units N/mm^2. To get 2000 N on this surface (one end of the beam) you calculate:
p = F / A = 2000 / 0.005 = 400000 N/mm^2
These inputs lead to a result of a maximum absolute displacement of 0.06359 m. To see the result actually deformed in Elmer Post, enter the following two lines in the Elmer Post command line (bottom of main window):
math n0=nodes
math nodes=n0+Displacement
display
To get an exaggerated deformation (for example 5 times):
math n0=nodes
math nodes=n0+5*Displacement
display
Instead of entering the last command "display" you can also left-mouseclick the psychedelic looking button on the right.
The beam tutorial is correct. The force works on the smallest area of 0.1 * 0.05 = 0.005 m^2. The confusing label "Force" in the Linear Elastic boundary condition is actually a pressure. So you enter something with for example the units N/mm^2. To get 2000 N on this surface (one end of the beam) you calculate:
p = F / A = 2000 / 0.005 = 400000 N/mm^2
These inputs lead to a result of a maximum absolute displacement of 0.06359 m. To see the result actually deformed in Elmer Post, enter the following two lines in the Elmer Post command line (bottom of main window):
math n0=nodes
math nodes=n0+Displacement
display
To get an exaggerated deformation (for example 5 times):
math n0=nodes
math nodes=n0+5*Displacement
display
Instead of entering the last command "display" you can also left-mouseclick the psychedelic looking button on the right.
Re: Displacement and tensions value in a elastic beam
p = F / A = 2000N / (0.05m x 0.1m) = 400,000 N/m^2
i think is in meter square and not millimeter square
i think is in meter square and not millimeter square
Re: Displacement and tensions value in a elastic beam
Vespa
Your Formula is faulty :
<Displacement_y = Force * length^3 / (8 * Youngs_Modulus * I)>
You divide with 8 it should be 3
Displacement_y = Force * length^3 / (3 * Youngs_Modulus * I)
Multiplying your result : 8/3 gives the 0.064m.
Your Formula is faulty :
<Displacement_y = Force * length^3 / (8 * Youngs_Modulus * I)>
You divide with 8 it should be 3
Displacement_y = Force * length^3 / (3 * Youngs_Modulus * I)
Multiplying your result : 8/3 gives the 0.064m.